Detail Creation Dialog

The detail creation dialog can be opened for any body (multiple bodies) or fragment via the context menu.

 

 

The command allows you to create a fragment based on a body (or multiple bodies) in an assembly, and assembly units based on fragments. The command also allows you to open a body or fragment in a separate document.

●You can select a body and place it in a fragment.

●You can select multiple bodies and place them in a fragment. The selected bodies will be moved to the fragment.

●You can select multiple bodies and a single fragment and place them in the fragment. The selected bodies and the selected fragment are transferred to the fragment.

●If you want to put several fragments in a separate fragment in the assembly, i.e. to create a build unit, this action can be performed using the "Assembly Structure” window: Create Subassembly, or via the context menu: Subassembly > Create (see section "Assembly unit creation"). The command for assembly units creation will be carried out through the fragment creation dialog.

Prototype. The option affects the default commands in the Ribbon and the standard. You can switch commands in the Ribbon.

Part Number and Description. The options are similar to the fragment creation dialog.

Do Not Save. This option allows you to open a body or fragment in a separate document. If necessary, you can save the viewed document with <Ctrl+S> Save.

Create Fragment. The body to which you applied the Create Fragment command is replaced with a fragment with a separate source file. All body model tree is moved into the fragment file. If necessary, reference element and (or) derived objects will be created (see "Reference element" section for details).

Create Adaptive Fragment. The body to which we applied the Create Adaptive Fragment command is replaced with a fragment with a separate source file. All body model  tree is moved into the fragment file. If reference elements are created during the command execution, they will be added into the geometric parameters of the fragment.

If you create an adaptive fragment (Create Adaptive Fragment) from a body (or bodies), and the body can be completely transferred from the source file to the generated fragment file, reference elements will not be created. Accordingly, the geometric parameters of the fragment will not be created, and the fragment will be non-adaptive.

Any fragment created with the Detail > Create command (both Create Fragment and Create Adaptive Fragment) can then be edited in the context of the assembly and reference elements can be created with the <3RE> Reference Element command.

Open Saved Document. If the flag is enabled, after selecting Create Fragment or Create Adaptive Fragment, the created fragment will be opened in T-FLEX CAD.

Additional options for creating fragments are available in the drop-down list.

Assembly document parameters. When this option is enabled, all parameters from the assembly document (the document from which the body is placed in the fragment) that are set in the <ST> Document Parameters command are passed to the part (the fragment to be created) .

External variables. When this option is enabled, all variables from the assembly file are passed to the part (the created fragment).

Geometry of the assembly document. This option is used for fragments created in the context of an assembly or adaptive fragments. Allows you to unload changes of the geometry on the basis of which a fragment was created in the context of an assembly or adaptive fragment. For example, an adaptive fragment was added to an assembly. If you have added an adaptive fragment and the geometry of its associated features has changed, you can upload the changes to the detail file. If the flag is disabled, the part is created based on the geometry that existed when the adaptive fragment was inserted.

Supplement from assembly document. Allows you to immediately move a fragment or body supplements from the assembly to the detail. For example, a fragment was added to an assembly and a hole was made in it. The supplement option has been activated for this hole. This supplement can be transferred to the part file with the fragment.

Combine initial operations. If a fragment contains several bodies, they can be combined into one body from the assembly. For example, if the bodies of a fragment were supplemented in an assembly in such a way that elements of different bodies were used in the same command, such supplement cannot be transferred to the fragment without combining the bodies.

 

See also: Top-down Assembly Design, Create Detail Using Detail > Create Command, Assembly unit creation, 3D Fragment Supplement, Fragment Geometry Check, Saving Geometry from Assembly to Separate File