Using Boolean Operation when Creating Other Operations

Numerous 3D modeling operations of T-FLEX CAD allow automatic creation of a Boolean. The body being created in those operations is always the tool of the Boolean. The target is selected among all existing bodies of the 3D model.

 

To use created body in Boolean operation:

1.Activate Boolean operation by on the following automenu option:

Automenu option will be highlighted in blue upon activation.

2.Change operation mode if necessary by + hold on the Boolean operation Mode automenu option and selecting desired mode from the drop-down:

Smart Mode way of operation

•Subtraction applied when body to be created and target body intersect each other.

•Subtraction applied when body to be created lays fully within the target body.

•Addition applied when body to be created touches (but do not intersect) target body.

•No Boolean operation applied when target body lays within Extrusion body or when there is an error in bodies penetration type calculation or when none of the aforementioned conditions are valid.

 

3.Select Target Body if necessary using following automenu option:

Body selected as a Target is highlighted in yellow in the 3D scene.

Select Target Body option becomes available upon defining minimum data required for tool body creation.

If there's only one body in scene, it's selected as a Target Body automatically. New body created in the 3D modeling operation is always used as a second operand of the Boolean operation.

When user confirms operation creation, first the 3D modeling operation body being created, then the Boolean operation.

 

Dynamic preview, as well as wire-frame preview of the operation result, do not display result of a Boolean operation. Use Preview of Operation Result if you want to see the result of Boolean before operation creation. If selected Boolean does not yield a result, only 3D modeling operation result is displayed on preview.

Boolean operations on 3D fragments

Use of 3D fragments as operands is a unique feature of T-FLEX CAD. This significantly expands capabilities of creating parametric 3D models and assemblies. At the time of inserting a 3D fragment into an assembly, there is a provision of creating a Boolean with the assembly's bodies. For details on capabilities of using a 3D fragment as an operand, refer to the chapter Creating Boolean Operation Based on 3D Fragment, and the chapter Set Document Parameters, the section 3D.

When you insert a 3D fragment with option for automatic Boolean operation creation, the preview displays not only the inserted fragment, but also the result of the Boolean operation.